HEIDENHAIN SW 548328-05 DIN Programming - Manual (Page 340)

340
DIN programming
4.26 Milling cy
cles
Linear slot on lateral surface G792
G792 mills a slot from the current tool position to the end point. The
slot width equals the diameter of the milling cutter. Oversizes are not
taken into account.
Parameter combinations for definition of the end point: see help
graphic
Parameter combinations for definition of the milling plane:
 Milling floor XE, milling top edge XS
 Milling floor XE, milling depth J
 Milling top edge XS, milling depth J
 Milling floor XE
Example: G792
%792.nc
[G792]
N1 T8 G197 S1200 G195 F0.2 M104
N2 M14
N3 G110 C0
N4 G0 X110 Z5
N5 G0 X102 Z-30
N6 G792 K25 A45 XE97 J3 P2 F0.15
N7 M15
END
Parameters
Z Final point of slot
C Final angle. Final point of slot (for angle direction, see help
graphic)
K Slot length referenced to center of cutter
A Slot angle (reference: see help graphic)
XE Milling floor
XS Milling top edge
J Milling depth
 J>0: Infeed direction –X
 J<0: Infeed direction +X
P Maximum approach (default: total depth in one infeed)
F Approach feed (infeed rate) (default: active feed rate)
 Rotate the spindle to the desired angle position before
calling G792.
 If you use a spindle positioning device (no C axis), a
radial slot is machined parallel to the Z axis.
 If J or XS is defined, the tool approaches to safety
clearance in X and then mills the slot. If J and XS are not
defined, the milling cycle starts from the current tool
position.