HEIDENHAIN iTNC 530 (60642x-04) - Manual (Page 244)

244 Programming: Programming Contours
6.4 P
a
th cont
ours—Car
te
sian coor
dinat
e
s
Example: Linear movements and chamfers with Cartesian coordinates
0 BEGIN PGM LINEAR MM
1 BLK FORM 0.1 Z X+0 Y+0 Z-20 Define the workpiece blank for graphic workpiece simulation
2 BLK FORM 0.2 X+100 Y+100 Z+0
3 TOOL CALL 1 Z S4000 Call the tool in the spindle axis and with the spindle speed S
4 L Z+250 R0 FMAX
Retract the tool in the spindle axis at rapid traverse FMAX
5 L X-10 Y-10 R0 FMAX Pre-positioning the tool
6 L Z-5 R0 F1000 M3
Move to working depth at feed rate F = 1000 mm/min
7 APPR LT X+5 Y+5 LEN10 RL F300 Approach the contour at point 1 on a straight line with tangential
connection
8 L Y+95 Move to point 2
9 L X+95 Point 3: first straight line for corner 3
10 CHF 10 Program a chamfer with length 10 mm
11 L Y+5 Point 4: 2nd straight line for corner 3, 1st straight line for corner 4
12 CHF 20 Program a chamfer with length 20 mm
13 L X+5 Move to last contour point 1, second straight line for corner 4
14 DEP LT LEN10 F1000 Depart the contour on a straight line with tangential connection
15 L Z+250 R0 FMAX M2 Retract the tool, end program
16 END PGM LINEAR MM
X
Y
9 5
95
5
10
10
20
20
1 4
2
3