HEIDENHAIN SW 54843x-03 DIN Programming - Manual (Page 524)

524 DIN programming for the Y axis
6.6 Linear and cir
c
ular mo
v
e
ments in the Y axis
6.6 Linear and circular movements
in the Y axis
Milling: Linear movement G1
G1 moves the tool on a linear path at the feed rate to the "end point."
The execution of G1 varies depending on the working plane:
 G17 Interpolation in the XY plane
 Infeed in Z direction
 Angle A—reference: positive X axis
 G18 Interpolation in the XZ plane
 Infeed in Y direction
 Angle A—reference: negative Z axis
 G19 Interpolation in the YZ plane
 Infeed in X direction
 Angle A—reference: positive Z axis
Parameters
X
End point (diameter)
Y End point
Z End point
AN Angle (reference: depends on the working plane)
Q Point of intersection. End point if the circular arc intersects a
line segment or another circular arc (default: 0):
 0: Near point of intersection
 1: Far point of intersection
BR Chamfer/rounding. Defines the transition to the next contour
element. When entering a chamfer/rounding, program the
theoretical end point.
 No entry: Tangential transition
 BR=0: No tangential transition
 BR>0: Radius of rounding
 BR<0: Width of chamfer
BE Special feed factor for chamfer/rounding arc (default: 1)
Special feed rate = active feed rate * BE (0 < BE <= 1)
Programming X, Y, Z: Absolute, incremental, modal or "?"