HEIDENHAIN TNC 410 - Manual (Page 97)

84 6 Programming: Programming Contours
Example: Circular movements with Cartesian coordinates
6.4 P
ath Cont
ours — Car
tesian Coor
dinat
es Example: Circular movements with Cartesian coordinates
0 BEGIN PGM CIRCULAR MM
1 BLK FORM 0.1 Z X+0 Y+0 Z-20
2 BLK FORM 0.2 X+100 Y+100 Z+0
3 TOOL DEF 1 L+0 R+10
4 TOOL CALL 1 Z S4000
5 L Z+250 R0 FMAX
6 L X-10 Y-10 R0 F MAX
7 L Z-5 R0 F1000 M3
8 APPR LCT X+5 Y+5 R5 RL F300
9 L X+5 Y+85
10 RND R10 F150
11 L X+30 Y+85
12 CR X+70 Y+95 R+30 DR-
13 L X+95
14 L X+95 Y+40
15 CT X+40 Y+5
16 L X+5
17 DEP LCT X-20 Y-20 R5 R0 F1000
18 L Z+250 R0 FMAX M2
19 END PGM CIRCULAR MM
Define blank form for graphic workpiece simulation
Define tool in the program
Call tool in the spindle axis and with the spindle speed S
Retract tool in the spindle axis at rapid traverse FMAX
Pre-position the tool
Move to working depth at feed rate F = 1000 mm/min
Approach the contour at point 1 on a circular arc with
tangential connection
Point 2: first straight line for corner 2
Insert radius with R = 10 mm, feed rate: 150 mm/min
Move to point 3: Starting point of the arc with CR
Move to point 4: End point of the arc with CR, radius 30 mm
Move to point 5
Move to point 6
Move to point 7: End point of the arc, radius with tangential
connection to point 6, TNC automatically calculates the radius
Move to last contour point 1
Depart the contour on a circular arc with tangential connection
Retract in the tool axis, end of program
X
Y
95 5
95
5
85
40
40 30 70
R10
R30