HEIDENHAIN TNC 360 User Manual - Manual (Page 182)

8-29 TNC 360
8 Cycles
8.3 SL Cycles
Rough out
Finishing
Example: Overlapping pockets with islands
Inside machining with pilot drilling, roughing out
and finishing.
PGM 360830 is based on 360825:
The main program has been expanded by the
cycle definition and cycle calls for pilot drilling
and finishing.
The contour subprograms 1 to 4 are identical to
those in PGM 360825 (see page 8-25) and are
to be added after block 39.
0 BEGIN PGM 360830 MM
1 BLK FORM 0.1 Z X+0 Y+0 Z–20
2 BLK FORM 0.2 X+100 Y+100 Z+0
3 TOOL DEF 1 L+0 R+2.2 ..................................... Drill
4 TOOL DEF 2 L+0 R+3 ........................................ Rough mill
5 TOOL DEF 3 L+0 R+2.5 ..................................... Finish mill
6 CYCL DEF 14.0 CONTOUR GEOM.
7 CYCL DEF 14.1 CONTOUR LABEL 1/2/3/4
8 CALL LBL 10
9 STOP M6
10 TOOL CALL 1 Z S 2000
11 CYCL DEF 15.0 PILOT DRILL
12 CYCL DEF 15.1 SET UP –2 DEPTH –10
13 CYCL DEF 15.2 PECKG –5 F500 ALLOW +2.8
14 L Z+2 R0 FMAX
15 CYCL CALL M3
16 CALL LBL 10
17 STOP M6
18 TOOL CALL 2 Z S 1750
19 CYCL DEF 6.0 ROUGH-OUT
20 CYCL DEF 6.1 SET UP –2 DEPTH –10
21 CYCL DEF 6.2 PECKG –5 F100 ALLOW +2
22 CYCL DEF 6.3 ANGLE +0 F500
23 L Z+2 R0 FMAX
24 CYCL CALL M3
25 CALL LBL 10
26 STOP M6
27 TOOL CALL 3 Z S 2500
28 CYCL DEF 16.0 CONTOUR MILLING
29 CYCL DEF 16.1 SET UP –2 DEPTH –10
30 CYCL DEF 16.2 PECKG –5 F100 DR– F500
31 L Z+2 R0 FMAX
32 CYCL CALL M3
33 CALL LBL 10
34 L Z+20 R0 FMAX M2 ......................................... Retract and rapid return
35 LBL 10
36 TOOL CALL 0 Z .................................................. Tool change
37 L Z+100 R0 FMAX
38 L X–20 Y–20 R0 FMAX
39 LBL 0
From block 40: add the subprograms listed on page 8-25
63 END PGM 360830 MM
Pilot drilling