HEIDENHAIN TNC 360 User Manual - Manual (Page 113)

5-29 TNC 360
5 Programming Tool Movements
5.5 Path Contours – Polar Coordinates
Example for exercise: Milling a hexagon
Corner point coordinates:
1 PA = 180° PR = 45 mm
2 PA = 120° PR = 45 mm
3 PA = 60° PR = 45 mm
4 PA = 0° PR = 45 mm
5
PA = 300° PR = 45 mm
6 PA = 240° PR = 45 mm
Milling depth: Z = –10 mm
Tool radius: R = 5 mm
–10
50
50
5
5
CC
60
°
R =45
Y
X
Z
100
100
1
2
3
4
5
6
Part program
0 BEGIN PGM 360529 MM
1 BLK FORM 0.1 Z X+0 Y+0 Z–20
2 BLK FORM 0.2 X+100 Y+100 Z+0
3 TOOL DEF 1 L+0 R+5
4 TOOL CALL 1 Z S 1000
5 CC X+50 Y+50
6 L Z+100 R0 FMAX M6
7 LP PR+60 PA–190 R0 FMAX
8 L Z–10 FMAX M3
9 LP PR+45 PA+180 RL F100
10 LP PA+120
11 LP PA+60
12 LP IPA–60
13 LP PA–60
14 LP PA+240
15 LP PA+180
16 LP PR+60 PA+170 R0 FMAX ............................. Retract the tool and end the program
17 L Z+100 FMAX M2
18 END PGM 360529 MM
General data and first contour point (corner point 1)
Corner points 2 to
6
and last contour point at 1 ;
absolute and incremental programming