HEIDENHAIN SW 54843x-02 DIN Programming - Manual (Page 412)

412 DIN programming
4.35 G codes fr
om pr
evious contr
o
ls Recessing G86
G86 machines simple radial and axial recesses with chamfers. From
the tool position, the control determines whether a radial or axial
recess, or an inside or outside recess is to be machined.
"Oversize" programmed: First roughing, then finishing
G86 machines chamfers at the sides of the recess. If you do not wish
to cut the chamfers, you must position the tool at a sufficient distance
from the workpiece. Calculate the starting position XS (diameter) as
follows:
Parameters
X
Base corner point (diameter)
Z Base corner point
I Radial recess: Oversize
 I>0: Oversize (roughing and finishing)
 I=0: No finishing
Axial recess: Recess width
 I>0: Recess width
 No input: Recess width = tool width
K Radial recess: Recess width
 K>0: Recess width
 No input: Recess width = tool width
Axial recess: Oversize
 K>0: Oversize (roughing and finishing)
 K=0: No finishing
E Dwell time (for chip breaking)—(default: length of time for one
revolution)
 With finishing oversize: Only for finishing
 Without finishing oversize: For every recess
Example: G86
. . .
N1 T30 G95 F0.15 G96 S200 M3
N2 G0 X62 Z2
N3 G86 X54 Z-30 I0.2 K7 E2 [radial]
N4 G14 Q0
N5 T38 G95 F0.15 G96 S200 M3
N6 G0 X120 Z1
N7 G86 X102 Z-4 I7 K0.2 E1 [axial]
. . .
XS = XK + 2 * (1.3 – b)
XK: Contour diameter
b: Chamfer width
 The tool radius compensation is active.
 Oversizes are not taken into account.