HEIDENHAIN MANUALplus 4110 - Manual (Page 292)

292 6 DIN Programming
6.5 Simple Linear and Cir
c
ular Mo
v
e
ments
6.5 Simple Linear and Circular
Movements
Linear path G1
Geometry command: G1 defines a linear segment in a contour.
Machining command: The tool moves on a linear path at feed rate to
the end point X, Z.
Parameters
 X end point (diameter value)
 Z end point
 A angle —for angle direction, see graphic support window.
 B chamfer/rounding: At the end of the linear path you can program
a chamfer/rounding or a tangential transition to the next contour
element.
„ No entry: Tangential transition
„ B=0: No tangential transition
„ B>0: Radius of rounding
„ B<0: Width of chamfer
 E special feed rate for chamfer/rounding—default: Active feed
rate
 Q point of intersection (default: Q=0): Specifies the end point if
two solutions are possible (see graphic support window).
Example: G1
%1.nc
[G1]
N1 T3 G95 F0.25 G96 S200 M3
N2 G0 X0 Z2
N3 G42
N4 G1 Z0
N5 G1 X20 B-0.5
N6 G1 Z-12
N7 G1 Z-24 A20
N8 G1 X48 B6
N9 G1 Z-52 B8
N10 G1 X80 B4 E0.08
N11 G1 Z-60
N12 G1 X82 G40
END